Simulation of welding using MSC.Marc. Paper reference number:

Size: px
Start display at page:

Download "Simulation of welding using MSC.Marc. Paper reference number:"

Transcription

1 Simulation of welding using MSC.Marc Paper reference number: Tor Morten Olsen 1, Henrik Runnemalm 1 and Daniel Berglund 1, 2 1 Volvo Aero Corporation, Trollhettan, Sweden Tor-morten.olsen@volvo.com +46 (0) Henrik.runnemalm@volvo.com +46 (0) Luleaa University of Technology, Luleaa, Sweden Daniel.berglund@volvo.com +46 (0) Abstract Simulation of welding requires the user to select between 2D, 3D shell and 3D solid models in different situations. An investigation regarding capability of MSC.Marc in simulation of welding is presented. The investigation focuses on differences between 3D shell- and 3D solid-models.

2 INTRODUCTION It is desirable to control and govern the residual deformations and stresses, which are generated in the component via different manufacturing process, in this case welding. Predictability of a component s response to the heat input from welding is important when manufacturing high precision components. Today, mainly experimental tests are used to determine the material response caused by different welding methods and parameters. Due to the high pricing on aerospace components, these tests are expensive. One way to workaround these costly tests would be to utilise simulation tools by means of the Finite Element Method (FEM). FEM has proven to be a versatile tool for predicting a component s response to various thermal and mechanical loads. FEM also offers the possibility to examine different aspects of the manufacturing process without having a physical prototype of the product. It is widely used for structural analyses, but due to lack of high temperature material data and sufficient computational power, it is not commonplace to apply FEM to manufacturing processes. The nonlinear nature of manufacturing processes makes the simulation both time consuming and a sophisticated challenge for the engineers. FEM applied on welding has been performed since the early seventies, [ref. 1] The work done in this paper is an extension on previous related work at Volvo Aero Corporation [ref. 2, 3]. The material response, in terms of deformations, during the welding simulation for the shell model and the solid model are presented. The aspect of choosing either a shell or solid model is discussed with respect to simulation accuracy. PROBLEM DEFINITION Two 3mm thick plates made of Inconel 718 were to be welded together. The hatched areas in Figure 1 represent a clamping device which prescribes the boundary conditions of the FE model with no mechanical degrees of freedom. The rest of the plate is unconstrained. Welding direction is left to right and the weld path is identical to the line of symmetry. Protecting gas swept the backface of the weldseam. Process parameters are described in Figure 2 and Table 1. After cooling, the plates were released from the fixturing device and the residual shrink at distance ab, ac and cd were measured for both the shell and the solid model. Shrink is defined as difference before and after welding in deformation between two geometrical points. Table 1 Process parameters that governs heat input to plates Parameter description Value The "a" value of the ellipse, Figure [mm] The "b" value of the ellipse, Figure [mm] The "c-front" value of the ellipse, Figure [mm] The "c-rear" value of the ellipse, Figure [mm] The velocity of the arc 2.17 [mm/s] Nominal effect from welding machine (P = U I) 735 [W]

3 Clamped 20 a 15 b c d 15 Clamped Figure 1 Geometry of plates, boundary conditions and measurement points Flux q Figure 2 The shape of the double elliptic heat source. ANALYSIS Analyse input The solid model was made up of 8-noded hexagonal elements, whereas the shell model had 4- noded thick shell elements, MSC.Marc element type number 4 and 75, respectively, [ref. 5]. The solid elements utilised the constant dilatation element formulation. Simulation using the assumed strain formulation was also compared with the standard formulation for solid elements. To introduce the moving heatsource to the analysis, an in-house developed user subroutine is utilised. This allows the weldtorch to be simulated as a moving double ellipsoidal heat source,

4 first described by Goldak et al. [ref. 4]. The doubleellipsoid is defined in Figure 2 and Table 1. The weld path is generated separately in the CAD software I-DEAS. The thermomechanical analysis was performed using the so-called staggered approach. This means that solution of the thermal matrix is done using the geometry matrix of last converged mechanical increment. The error introduced by letting the geometry of the thermal solution lag one step after the mechanical solution is neglectable, as the timesteps in welding analysis are small, often in the order of 10-2 s to s. The heat flux is inserted at every integration point that is encircled by the ellipsoid at each increment. The energy is applied to the shells as a face flux and as volumetric flux to the solids. When performing the analysis with shell structures, the joining of material is done by activating links as the heatsource moves along the weldpath. Joining of material in the solid model is done by first deactivating elements along the weldpath, then revive these elements as the heatsource encounters them. Another feature is that stresses and strains are to be reset to zero when the material reaches the melting temperature. In the present analyses this was only implemented for the solid elements. For shells then, the stresses from material expansion will therefore impact the remainder of the analysis. Figure 3 shows how stresses differ in solid and shell model as temperatures exceed T melt at some instant during welding [MPa] Solid model Shell model [mm] Figure 3 Distance from centre of weldpool (x=0) vs. Von Mises stress Large deformation and large plastic strains were accounted for and the additive decomposition of elastic, plastic and thermal strain contributions was utilized for the stress recovery process. The analysis ran using a regular elasto-plastic material model with von Mises yield criteria. The material data included mechanical properties, specific heat and conductivity as functions of temperature. The density is only given as a value at room temperature. The staggered approach will automatically force the FE code to account for density variation as the temperature changes in the material. The thermal conductivity was increased by a magnitude of 10 when T T melt. This accounts for stirring of the liquid weldpool. T melt is set to1570k. For the shell analysis, equal heat input to top and backface was implemented. This gives a constant temperature through thickness. To minimize the errors of introducing constant temperature through the thickness and to account for the protecting gas at the backface, an increased convection was applied on the backface.

5 Analyse results Simulation of welding is in many respects time consuming. The time spent in modelling is usually more time consuming than the actual runtime. However, in parametric studies the time of a run is essential. The analyses presented in this paper has been run on a SUN Ultra MHz workstation. The runtimes for each analysis can be seen in Table 2. The assumed strain and the constant dilatation approach gave the same results for this specific case, but the assumed strain formulation increased the computational demands drastically. Table 2 Solids vs. shells, computational demands Solid model Shell model # elements # nodes nodes dofs # increments # layers NA 11 # solution time ~ 3 days, 15 hours (two proc.) ~ 5 days, 8 hours (two proc. & ass. strain) 2 hours 45 minutes The application of an increased convection induced bending components that forces the shell plate into the preferred displacement mode. The heat input to the solid model corresponds to the elliptic model. Figure 4 shows the temperature contour lines of a small part of the weldseam in the solid model as the torch passes it. Figure 4 Contour lines of temperature distribution [K] in weld seam. Displacement enlarged five times The actual welding of the plates takes 70 seconds. Figure 5 shows the heat absorbed by the plates at an arbitrarily chosen interval between t=35s and t=40s. Figure 5 clearly shows a cyclic flux going into the shell model. This cyclic behaviour arises since the double ellipsoid encircles a varying number of integration points where heat can flow into the structure. The cycle spans 2,4seconds, in which the center of the heatsource travels approximately one element length. At instants t=35s, t=37,4s and t=39,8s the ellipsoid encounters only two integration points that

6 receives noticeable energy. The average flux input to shell model between t=35s and t=40s is 440W while the solid model receives 650W. The cyclic variation of the flux into the shell model spans between 62% to 76% of the constant flux obtained by the solid model. Heat flux into FEM models Flux [W] Shell model Solid model/domain1 Solid model/domain2 Solid model Total Time [s] Figure 5 Flux into structures as torch crosses domain boundaries. Domain 1 & 2 corresponds to CPU number. In the case of the solid model the doubleellipsoid always encircles more integration points. The solid model thus receives a higher and constant flux. Between 35 and 40 seconds the weld arc moves across the element domain boundaries. The total flux remains constant, which shows that MSC.Marc handles the transition from one element domain to another (2 CPUs), also with the subroutine running. The flux into the dense meshed solid model is 89% of the nominal effect, 735W. For comparison, an identical solid model, but with only two elements through thickness was inspected with respect to heat flux. The result suggests that two brick elements through thickness are sufficient with respect to amount of heat absorbed by the model. The shell model reaches maximum temperatures in the weldpool between 1690 and 1870 K depending on amount and shape of heat flux absorbed by the model. The shape of the weldpool is also varying with the heat flux absorbed by the shell model. The width of the weldpool at topface changes between 1mm and 4mm. This variation shows the sensivity of the mesh with respect to energy input. The solid model reaches maximum temperatures in weldpool between 1633 and 1643 K. The width of the weldpool at topface is constant and equals 6.0mm. The models have similar displacement modes during welding, but displacements out of plane is smaller for the solid model, decreasing its resultant displacement compared to the shell model, see Figure 7. The resultant displacement is defined as res = ( x 2 + y 2 + z 2 ). This means that four elements through thickness and with the constant dilatation approach is not enough to include correct bending behaviour of the plate. The solid model thus becomes too stiff. Table 3 shows the direction conventions for the shell and the solid model. Table 4 presents the residual deformations predicted by the simulations.

7 Table 3 Direction conventions in shells and solids Element Welding direction Perpendicular to w. direction (inplane) Shell 11, σ 11 22, σ 22, N/A Thickness direction Solid 33, σ 33, 11, σ 11, 22, σ 22 Table 4 Shrinkage perpendicular to welding direction Shrink at distance ab Shrink at distance cd Shrink at distance ac Shell model 0,23 mm 0,28 mm 0,07 mm Solid model 0,17 mm 0,18 mm 0, Point 1: (50, -5.0) mm Point 2: (70, -5.0) mm Weld path is left to right. Origo is at weld start. Figure 6 Definition of points 1 and 2. Resultant displacements, shell & solid mode l 2.00E-01 Shell, point1 1.50E-01 [mm] 1.00E-01 Solid, point1 Solid, point2 Shell, point2 5.00E E E E E E E E E+01 Time [s] Figure 7 Displacements during welding, res = ( x 2 + y 2 + z 2 ) As mentioned, the resetting of stresses and strains is not currently implemented for shell elements. This results in stress components where the largest, σ 11, is -230 MPa and σ 22 equals -140 MPa when T > T melt. In the solid model, the equivalent stresses at nodes are less than 10 MPa for T > T melt. Since the stresses are reset in the integration points, the projected stresses at the nodes differ from zero. Thus, the implementation of resetting in solid elements is sufficient.

8 From Figure 8 at t=60s, we have the midplane stress components σ MPa and σ MPa in the shell model. Stress components on topface are σ MPa and σ 22 0MPa (not shown in picture). The stress contribution from bending is approximately 100 MPa parallel to weld and 120 MPa perpendicular to weld. Thus the plate is dominated by pure tensile stresses rather than local bending. This is expected as the plate is thoroughly clamped. Similarly inspection of solid model in Figure 9 yields stress contributions from bending; 30 MPa in welding direction and zero perpendicular to the weld, as σ 11 is constant through thickness. Due to poor bending behaviour in the solid model, the solid model becomes too stiff. This gives smaller displacements and higher stress concentrations during welding compared to the shell model. As can be calculated from Figure 8 and Figure 9, the maximum equivalent stresses as the torch passes are 13% higher in the solid model. This is mainly due to stresses in thickness direction. After the heatsource has passed, the inplane stresses rise much steeper in the solid model. This is partly explained above, as energy is transformed to plate bending in the shell model and mainly to tensile stresses in the solid model. Stresses in shell model Temperature/2 [K] 400 σ [MPa] σ 22 σ Time[s] Figure 8 Temperature [K] and stresses [MPa] in point 1 (Figure 6), shell model. Middle of plate thickness

9 Stress components in solid model Temperature/2 [K] σ [MPa] σ σ 22 σ Time[s] Figure 9 Temperature [K] and stresses [MPa] in point 1 (Figure 6), solid model. Middle of plate thickness DISCUSSIONS There is an uncertainty in the loss of energy between welding equipment and what is actually landed in the weld seam. In these analyses the solid model received 88% which is believed to be too high. The shell model received 60% of the nominal effect, which is believed to be closer to reality. The FEM simulations assume a perfectly rigid clamping of the plates in the fixturing device. In a real welding process this might not be the case, as the plates might slide inside the fixture to increase the weld gap. With the observed magnitude of the reaction forces at the interface between plate and fixture this likely happens. When sliding, the weld gap will increase, causing increased weldpool width and thus a larger area where substantial shrink occurs. CONCLUSIONS When using element number 7 in MSC.Marc in conjunction with thermomechanically coupled analysis with plasticity, no additional accuracy was gained using the assumed strain formulation instead of only constant dilatation formulation. The heat source defined by Goldak's ellipsoid is very dependent upon inplane element size. Good consistency regarding measured shrink and computations gives increased control of the components final shape. Both shell and solid models predict global plate deformations at the same magnitude. The shell model is not sufficient for determining local deformations near the weld seam, as the mesh is too coarse and the heat flux shows cyclic variation.

10 To make FE welding analysis on complex prototypes more commonplace, better hardware/software combinations are desired. Joining multiple processors and adaptive meshing would be a great advance. When sufficient combinations of hardware and software makes FE weld analysis applicable on large models, initial weld testing on real components will be drastically reduced. This will also enable design- and welding engineers to tailor-make desired deformations, residual stresses or a preferred microstructure onto a component though welding. This might be a certain amount of compressive stresses to enhance the fatigue properties of an engine component. One might also be interested in capturing a sequence of manufacturing operations, for example combining welding and heat treatment. The latter combination using MSC.Marc and CFD has proven useful at Volvo Aero Corporation. Finally, in the future, the use of manufacturing simulation makes it possible to run FE analyses with operating loads with correct prestressed components. This will make it easier to reveal potential operating failures. ACKNOWLEDGEMENTS This work is part of the results gained in EU s 5 th frame project MMFSC, contract number GRD We would also like to thank MSC.Software Support for subroutine to reset stresses and strains. REFERENCES 1. Thermal stress analysis of metals with temperature dependent mechanical properties. Ueda Y. and Yamakawa T. JWRI, Vol 2, No. 2, Three-Dimensional Finite Element Simulation of Laser Welded Stainless Steel Plate D. Berglund, L.E. Lindgren and A. Lundbaeck. Accepted for 7 th Int. Conf. On numerical Methods in Industrial Forming Processes, Japan Welding Simulation using FEM- Joining of Geometries. M. Sc. thesis by Joergen Naeslund. Volvo Aero Corporation & Luleaa Technical University, Sweden A new finite element model for welding heat sources. J.A Goldak, Chacravarti A. and M. J. Bibby. AIME, Vol. 15B, No.2, Marc manuals MSC.Marc Volume B Element Library, version MSC Software Corporation

Simulation of Residual Deformation from a Forming and Welding Process using LS-DYNA

Simulation of Residual Deformation from a Forming and Welding Process using LS-DYNA 13 th International LS-DYNA Users Conference Session: Simulation Simulation of Residual Deformation from a Forming and Welding Process using LS-DYNA Mikael Schill 1, Eva-Lis Odenberger 2 1 DYNAmore Nordic

More information

Recent Developments for Welding Simulations in LS-DYNA and LS-PrePost

Recent Developments for Welding Simulations in LS-DYNA and LS-PrePost 14 th International LS-DYNA Users Conference Session: Connections Recent Developments for Welding Simulations in LS-DYNA and LS-PrePost Mikael Schill DYNAmore Nordic AB, Linköping, Sweden Anders Jernberg

More information

CHAPTER 3 FINITE ELEMENT SIMULATION OF WELDING

CHAPTER 3 FINITE ELEMENT SIMULATION OF WELDING 47 CHAPTER 3 FINITE ELEMENT SIMULATION OF WELDING 3.1 INTRODUCTION Though welding process has many distinct advantages over other joining processes, it suffers from some major disadvantages like the evolution

More information

EFFECT OF WELDING SEQUENCES ON RESIDUAL STRESS IN SINGLE PASS BUTT WELDING OF SAE 1020 STEEL

EFFECT OF WELDING SEQUENCES ON RESIDUAL STRESS IN SINGLE PASS BUTT WELDING OF SAE 1020 STEEL EFFECT OF WELDING SEQUENCES ON RESIDUAL STRESS IN SINGLE PASS BUTT WELDING OF SAE 1020 STEEL Teke Sumit Sudhakar 1, Prof. P.P.Powar 2, Prof. R.R.Gad 3. 1 ME (CAD/CAM/CAE), 2 Associate Professor, 3 Assistant

More information

Repair Weld Simulation of Austenitic Steel Pipe

Repair Weld Simulation of Austenitic Steel Pipe Repair Weld Simulation of Austenitic Steel Pipe BÉZI Zoltán 1, a *, SZÁVAI Szabolcs 1,b 1 Bay Zoltán Nonprofit Ltd., Institute for Logistics and Production Engineering, 2 Iglói Str., 3519 Miskolc, Hungary

More information

Cold roll forming of a U-channel made of high strength steel

Cold roll forming of a U-channel made of high strength steel Journal of Materials Processing Technology 186 (2007) 77 81 Cold roll forming of a U-channel made of high strength steel M. Lindgren Dalarna University, Sweden Received 16 June 2005; received in revised

More information

Determination of the residual stress distribution of steel bridge components by modelling the welding process

Determination of the residual stress distribution of steel bridge components by modelling the welding process EUROSTEEL 2017, September 13 15, 2017, Copenhagen, Denmark Determination of the residual stress distribution of steel bridge components by modelling the welding process Evy Van Puymbroeck*,a, Wim Nagy

More information

Modeling of Residual Stresses in a Butt-welded Joint with Experimental Validation

Modeling of Residual Stresses in a Butt-welded Joint with Experimental Validation Modeling of Residual Stresses in a Butt-welded Joint with Experimental Validation Vivek Srivastava* and AG Rao Naval Materials Research Laboratory (NMRL), Defence Research and Development Organization

More information

PREDICTION OF WELD INDUCED ANGULAR DISTORTION OF SINGLE SIDED AND DOUBLE SIDED FILLET JOINT BY SAW PROCESS

PREDICTION OF WELD INDUCED ANGULAR DISTORTION OF SINGLE SIDED AND DOUBLE SIDED FILLET JOINT BY SAW PROCESS 5 th International & 26 th All India Manufacturing Technology, Design and Research Conference (AIMTDR 2014) December 12 th 14 th, 2014, IIT Guwahati, Assam, India PREDICTION OF WELD INDUCED ANGULAR DISTORTION

More information

SIMULATION OF THE INFLUENCE OF FORMING ON RESIDUAL STRESSES AND DEFORMATIONS AFTER WELDING AND HEAT TREATMENT IN ALLOY 718

SIMULATION OF THE INFLUENCE OF FORMING ON RESIDUAL STRESSES AND DEFORMATIONS AFTER WELDING AND HEAT TREATMENT IN ALLOY 718 11th World Congress on Computational Mechanics (WCCM XI) 5th European Conference on Computational Mechanics (ECCM V) 6th European Conference on Computational Fluid Dynamics (ECFD VI) E. Oñate, J. Oliver

More information

Weld simulation in LS-DYNA and LS-PREPOST. Mikael Schill Anders Jernberg

Weld simulation in LS-DYNA and LS-PREPOST. Mikael Schill Anders Jernberg Weld simulation in LS-DYNA and LS-PREPOST Mikael Schill Anders Jernberg LS-DYNA One code strategy Combine the multi-physics capabilities into one scalable code for solving highly nonlinear transient problems

More information

The effect of residual stresses on the strain evolution during welding of thin-walled tubes

The effect of residual stresses on the strain evolution during welding of thin-walled tubes The effect of residual stresses on the strain evolution during welding of thin-walled tubes Maarten De Strycker 1,a, Wim Van Paepegem 2,b, Luc Schueremans 3,c and Dimitri Debruyne 4,d 1 MeM2P research

More information

Finite Element Simulation of Manufacturing Process of Chassis Side Members MT05.22

Finite Element Simulation of Manufacturing Process of Chassis Side Members MT05.22 Faculty of Mechanical Engineering Computational and Experimental Mechanics Finite Element Simulation of Manufacturing Process of Chassis Side Members MT05.22 W.Blom Supervisor: dr.ir. R.H.J. Peerlings

More information

Nonlinear Buckling Analysis on Welded Airbus Fuselage Panels

Nonlinear Buckling Analysis on Welded Airbus Fuselage Panels Nonlinear Buckling Analysis on Welded Airbus Fuselage Panels P. Reimers IWiS GmbH A. Gorba Airbus Deutschland GmbH Contents Overview FE - Model Analysis Results Comparison to Test Results Conclusion Discussion

More information

CST004. Modeling of Double-Ellipsoidal Heat Source for Submerged Arc Welding Process. Nareudom Khajohnvuttitragoon and Chainarong Srikunwong*

CST004. Modeling of Double-Ellipsoidal Heat Source for Submerged Arc Welding Process. Nareudom Khajohnvuttitragoon and Chainarong Srikunwong* Modeling of Double-Ellipsoidal Heat Source for Submerged Arc Welding Process Nareudom Khajohnvuttitragoon and Chainarong Srikunwong* Department of Mechanical and Aerospace Engineering Faculty of Engineering

More information

DYNAMIC RESPONSE ANALYSIS OF THE RAMA 9 BRIDGE EXPANSION JOINT DUE TO RUNNING VEHICLE

DYNAMIC RESPONSE ANALYSIS OF THE RAMA 9 BRIDGE EXPANSION JOINT DUE TO RUNNING VEHICLE DYNAMIC RESPONSE ANALYSIS OF THE RAMA 9 BRIDGE EXPANSION JOINT DUE TO RUNNING VEHICLE Tanan Chub-uppakarn 1, Adison Owatsiriwong 2* 1 Department of Civil Engineering, Faculty of Engineering, Prince of

More information

Numerical and Experimental Investigations on Welding Deformation

Numerical and Experimental Investigations on Welding Deformation Transactions of JWRI, Vol. 7 (8), No. Numerical and Experimental Investigations on Welding Deformation WANG Rui *, RASHED Sherif **, SERIZAWA Hisashi***, MURAKAWA Hidekazu**** and Jianxun ZHANG ***** Abstract

More information

Computing Welding Distortion: Comparison of Different Industrially Applicable Methods

Computing Welding Distortion: Comparison of Different Industrially Applicable Methods Computing Welding Distortion: Comparison of Different Industrially Applicable Methods D. Tikhomirov a, B. Rietman b, K. Kose c and M. Makkink d INPRO GmbH, Hallerstraße 1, 10587 Berlin, Germany a dmitrij.tikhomirov@inpro.de,

More information

Mechanical Integrity of Copper Canister Lid and Cylinder

Mechanical Integrity of Copper Canister Lid and Cylinder SKI Report 2003:05 Research Mechanical Integrity of Copper Canister Lid and Cylinder Marianne Karlsson January 2002 ISSN 1104 1374 ISRN SKI-R-03/05-SE SKI perspective Background and purpose of the project

More information

CHAPTER 7 FINITE ELEMENT ANALYSIS

CHAPTER 7 FINITE ELEMENT ANALYSIS 189 CHAPTER 7 FINITE ELEMENT ANALYSIS 7.1 SCOPE In Engineering applications, the physical response of the structure to the system of external forces is very much important. Understanding the response of

More information

SET PROJECT STRUCTURAL ANALYSIS OF A TROUGH MODULE STRUCTURE, IN OPERATION AND EMERGENCY Luca Massidda

SET PROJECT STRUCTURAL ANALYSIS OF A TROUGH MODULE STRUCTURE, IN OPERATION AND EMERGENCY Luca Massidda SET PROJECT STRUCTURAL ANALYSIS OF A TROUGH MODULE STRUCTURE, IN OPERATION AND EMERGENCY Luca Massidda Table of Contents Introduction... 2 Finite element analysis... 3 Model description... 3 Mirrors...

More information

by NISHIKAWA Hiroyuki, KATSUYAMA Jinya and ONIZAWA Kunio

by NISHIKAWA Hiroyuki, KATSUYAMA Jinya and ONIZAWA Kunio [ 27 p. 245s-250s (2009)] by NISHIKAWA Hiroyuki, KATSUYAMA Jinya and ONIZAWA Kunio Numerical simulations by thermal-elastic-plastic-creep analysis using finite element method (FEM) have been performed

More information

Combined butt joint welding and post weld heat treatment simulation using SYSWELD and ABAQUS

Combined butt joint welding and post weld heat treatment simulation using SYSWELD and ABAQUS See discussions, stats, and author profiles for this publication at: http://www.researchgate.net/publication/258178486 Combined butt joint welding and post weld heat treatment simulation using SYSWELD

More information

Recent Developments in LS-DYNA to close the Virtual Process Chain for Forming, Press Hardening and Welding

Recent Developments in LS-DYNA to close the Virtual Process Chain for Forming, Press Hardening and Welding Recent Developments in LS-DYNA to close the Virtual Process Chain for Forming, Press Hardening and Welding Thomas Klöppel 1, Andrea Erhart 1, André Haufe 1, Tobias Loose 2 1 DYNAmore GmbH, ²Ingenieurbüro

More information

Validation of VrHeatTreat Software for Heat Treatment and Carburization

Validation of VrHeatTreat Software for Heat Treatment and Carburization Validation of VrHeatTreat Software for Heat Treatment and Carburization John Goldak a, Jianguo Zhou a, Stanislav Tchernov a, Dan Downey a, a Goldak Technologies Inc, Ottawa, Canada December 12, 2007 1

More information

SHEAR PANEL COMPONENT IN THE VICINITY OF BEAM-COLUMN CONNECTIONS IN FIRE

SHEAR PANEL COMPONENT IN THE VICINITY OF BEAM-COLUMN CONNECTIONS IN FIRE 8 th International Conference on Structures in Fire Shanghai, China, June 11-13, 2014 SHEAR PANEL COMPONENT IN THE VICINITY OF BEAM-COLUMN CONNECTIONS IN FIRE Guan Quan*, Shan-Shan Huang* and Ian Burgess*

More information

by MAEKAWA Akira, NODA Michiyasu, TAKAHASHI Shigeru, OUMAYA Toru, SERIZAWA Hisashi and MURAKAWA Hidekazu

by MAEKAWA Akira, NODA Michiyasu, TAKAHASHI Shigeru, OUMAYA Toru, SERIZAWA Hisashi and MURAKAWA Hidekazu [ 27 p. 240s-244s (2009)] by MAEKAWA Akira, NODA Michiyasu, TAKAHASHI Shigeru, OUMAYA Toru, SERIZAWA Hisashi and MURAKAWA Hidekazu This paper reports measured and estimated results of residual stress distributions

More information

A Review of Suitability for PWHT Exemption Requirements in the Aspect of Residual Stresses and Microstructures

A Review of Suitability for PWHT Exemption Requirements in the Aspect of Residual Stresses and Microstructures Transactions, SMiRT-23 Division IX, Paper ID 612 (inc. assigned division number from I to X) A Review of Suitability for PWHT Exemption Requirements in the Aspect of Residual Stresses and Microstructures

More information

FINITE ELEMENT ANALYSIS OF THERMAL TENSIONING TECHNIQUES MITIGATING WELD BUCKLING DISTORTION

FINITE ELEMENT ANALYSIS OF THERMAL TENSIONING TECHNIQUES MITIGATING WELD BUCKLING DISTORTION FINITE ELEMENT ANALYSIS OF THERMAL TENSIONING TECHNIQUES MITIGATING WELD BUCKLING DISTORTION Panagiotis Michaleris The Pennsylvania State University University Park, PA and Xin Sun Battelle Columbus, OH

More information

CHAPTER 7 ANALYTICAL PROGRAMME USING ABAQUS

CHAPTER 7 ANALYTICAL PROGRAMME USING ABAQUS 87 CHAPTER 7 ANALYTICAL PROGRAMME USING ABAQUS 7.1 GENERAL With the advances in modern computing techniques, finite element analysis has become a practical and powerful tool for engineering analysis and

More information

JJMIE Jordan Journal of Mechanical and Industrial Engineering

JJMIE Jordan Journal of Mechanical and Industrial Engineering JJMIE Jordan Journal of Mechanical and Industrial Engineering Volume 5, Number 6, Dec. 211 ISSN 1995-6665 Pages 553-557 On the Deformation Modes of Continuous Bending under Tension Test A. Hadoush*,a a

More information

A SIMPLIFIED ENGINEERING METHOD FOR A T-JOINT WELDING SIMULATION

A SIMPLIFIED ENGINEERING METHOD FOR A T-JOINT WELDING SIMULATION S867 A SIMPLIFIED ENGINEERING METHOD FOR A T-JOINT WELDING SIMULATION by Mato PERI] a*, Zdenko TONKOVI] b, Igor KARŠAJ b, and Dragi STAMENKOVI] c a Bureau of Energetics and Mechanical Engineering Ltd.,

More information

Experimental and Numerical Analysis of the Friction Welding Process for the 4340 Steel and Mild Steel Combinations

Experimental and Numerical Analysis of the Friction Welding Process for the 4340 Steel and Mild Steel Combinations WELDING RESERCH Experimental and Numerical nalysis of the Friction Welding Process for the 4340 Steel and Mild Steel Combinations model was developed that can be used as an industrial tool to predict evolution

More information

Modeling Component Assembly of a Bearing Using Abaqus

Modeling Component Assembly of a Bearing Using Abaqus Modeling Component Assembly of a Bearing Using Abaqus Bisen Lin, Ph.D., P.E. and Michael W. Guillot, Ph.D., P.E. Stress Engineering Services, Inc. Abstract: Assembly process of a bearing considered in

More information

THERMO-MECHANICAL ANALYSIS OF A CORNER WELDED JOINT BY FINITE ELEMENT METHOD

THERMO-MECHANICAL ANALYSIS OF A CORNER WELDED JOINT BY FINITE ELEMENT METHOD THERMO-MECHANICAL ANALYSIS OF A CORNER WELDED JOINT BY FINITE ELEMENT METHOD 1 K.Ashok Kumar 2 Dr. CH.Srinivasa Rao 3 T.N Charyulu 4 SCV Ramana Murthy Naidu 1 M.Tech. Scholar, Nova College of Engineering

More information

THE INFLUENCE OF RESIDUAL STRESS FIELDS AND SHEET THICKNESS ON STRESS DISTRIBUTIONS IN RIVETED JOINT

THE INFLUENCE OF RESIDUAL STRESS FIELDS AND SHEET THICKNESS ON STRESS DISTRIBUTIONS IN RIVETED JOINT Journal of KONES Powertrain and Transport, Vol. 7, No. 2 THE INFLUENCE OF RESIDUAL STRESS FIELDS AND SHEET THICKNESS ON STRESS DISTRIBUTIONS IN RIVETED JOINT El bieta Szymczyk Military University of Technology

More information

Manufacturingsimulation in the shipbuilding area. Simufact Eng. GmbH Schafstall, H.

Manufacturingsimulation in the shipbuilding area. Simufact Eng. GmbH Schafstall, H. Manufacturingsimulation in the shipbuilding area Simufact Eng. GmbH Schafstall, H. Simufact Engineering stands for Simulating Manufacturing More than 20 years of professional experience Over 50 high skilled

More information

Numerical simulation of dissimilar metal welding and its verification for determination of residual stresses

Numerical simulation of dissimilar metal welding and its verification for determination of residual stresses Focused on Fracture Mechanics in Central and East Europe Numerical simulation of dissimilar metal welding and its verification for determination of residual stresses Sz. Szávai Bay Zoltán Nonprofit Ltd.,

More information

Reliability into. for Biomedical. Devices: Finite Elelment Analyses. Applications CAE Associates

Reliability into. for Biomedical. Devices: Finite Elelment Analyses. Applications CAE Associates Designing i Reliability into Biomedical Devices: Finite Elelment Analyses for Biomedical Applications 2005 CAE Associates Designing Reliability into Biomedical Devices: Finite Element Analyses for Bio-Medical

More information

Flexural behaviour of a polymeric foam/glass-fibre composite: FE modelling and experimental testing

Flexural behaviour of a polymeric foam/glass-fibre composite: FE modelling and experimental testing Flexural behaviour of a polymeric foam/glass-fibre composite: FE modelling and experimental testing G. Belingardi, M. P. Cavatorta & L. Peroni Department of Mechanical Engineering, Politecnico di Torino,

More information

simufact.welding simufact.welding simufact engineering gmbh phone fax

simufact.welding simufact.welding simufact engineering gmbh phone fax simufact.welding simufact.welding simufact engineering gmbh phone +49 40 790 1620 fax +49 40 790 162 22 Program Introduction Simufact.Welding is a Pre- and Postprocessor-GUI for finite element welding

More information

FAILURE PREDICTION IN HONEYCOMB SANDWICH BEAMS UNDER LOW-VELOCITY IMPACT

FAILURE PREDICTION IN HONEYCOMB SANDWICH BEAMS UNDER LOW-VELOCITY IMPACT 18 TH INTERNATIONAL CONFERENCE ON COMPOSITE MATERIALS FAILURE PREDICTION IN HONEYCOMB SANDWICH BEAMS UNDER LOW-VELOCITY IMPACT I. Ivañez 1 *, C. Santiuste 1, E. Barbero 1, S. Sanchez-Saez 1 1 Department

More information

Simulation and Validation of TIG-Welding and Post Weld Heat Treatment of an Inconel 718 Plate

Simulation and Validation of TIG-Welding and Post Weld Heat Treatment of an Inconel 718 Plate Simulation and Validation of TIG-Welding and Post Weld Heat Treatment of an Inconel 718 Plate Andreas Lundbäck 1, Henrik Alberg 1 and Per Henrikson 2 1 Luleå University of Technology S-971 87 Luleå Sweden

More information

Numerical Modeling and Finite Element Analysis of Steel Sheathed Cold-Formed Steel Shear Walls

Numerical Modeling and Finite Element Analysis of Steel Sheathed Cold-Formed Steel Shear Walls Numerical Modeling and Finite Element Analysis of Steel Sheathed Cold-Formed Steel Shear Walls Shirin Esmaeili Niari, Behzad Rafezy & Karim Abedi Sahand University of Technology, P. O. Box 51335/1996,

More information

User Implemented Nitinol Material Model in ANSYS

User Implemented Nitinol Material Model in ANSYS Abstract User Implemented Nitinol Material Model in ANSYS Peter R. Barrett, P.E. Computer Aided Engineering Associates, Inc. Daniel Fridline, Ph.D. Computer Aided Engineering Associates, Inc. Nitinol is

More information

New approach to improving distortional strength of intermediate length thin-walled open section columns

New approach to improving distortional strength of intermediate length thin-walled open section columns New approach to improving distortional strength of intermediate length thin-walled open section columns R. S. Talikoti 1, K. M. Bajoria 2 1 Research Scholar (Email: rstalikoti@iitb.ac.in) 2 Associate Professor

More information

Finite element analyses of TMCP steel plates with consideration of edge masking

Finite element analyses of TMCP steel plates with consideration of edge masking Available online at www.sciencedirect.com Procedia Engineering 00 (2013) 000 000 CTAM 2013 The 37 th National Conference on Theoretical and Applied Mechanics (37th-NCTAM) The 1 st International Conference

More information

Study the pattern of J-profile along the crack front through 3D finite element analysis

Study the pattern of J-profile along the crack front through 3D finite element analysis Page 16 Study the pattern of J-profile along the crack front through 3D finite element analysis Abstract: Badrun Nahar Hamid a*, Michale J Baker b a Principal Scientific Officer, Atomic Energy Research

More information

APPLYING MSC/PATRAN AND MSC/NASTRAN TO IMPROVE THE DESIGN PERFORMANCE OF LARGE BULK MATERIALS HANDLING MACHINES

APPLYING MSC/PATRAN AND MSC/NASTRAN TO IMPROVE THE DESIGN PERFORMANCE OF LARGE BULK MATERIALS HANDLING MACHINES APPLYING MSC/PATRAN AND MSC/NASTRAN TO IMPROVE THE DESIGN PERFORMANCE OF LARGE BULK MATERIALS HANDLING MACHINES ABSTRACT R C Morgan BE MEng Sc FIE Aust CP Eng Principal Consultant - Structural, BHP Engineering

More information

FEM STRESS CONCENTRATION FACTORS FOR FILLET WELDED CHS-PLATE T-JOINT

FEM STRESS CONCENTRATION FACTORS FOR FILLET WELDED CHS-PLATE T-JOINT Engineering Review Vol. 32, Issue 3, 147-155, 2012. 147 FEM STRESS CONCENTRATION FACTORS FOR FILLET WELDED CHS-PLATE T-JOINT S. * G. Turkalj Department of Engineering Mechanics, Faculty of Engineering,

More information

PARAMETRIC STUDY OF FLANGE JOINT AND WEIGHT OPTIMIZATION FOR SAFE DESIGN AND SEALABILITY- FEA APPROACH Chavan U. S.* Dharkunde R. B. Dr. Joshi S.V.

PARAMETRIC STUDY OF FLANGE JOINT AND WEIGHT OPTIMIZATION FOR SAFE DESIGN AND SEALABILITY- FEA APPROACH Chavan U. S.* Dharkunde R. B. Dr. Joshi S.V. Research Article PARAMETRIC STUDY OF FLANGE JOINT AND WEIGHT OPTIMIZATION FOR SAFE DESIGN AND SEALABILITY- FEA APPROACH Chavan U. S.* Dharkunde R. B. Dr. Joshi S.V. Address for Correspondence Department

More information

Effects of the weld groove shape and geometry on residual stresses in dissimilar butt-welded pipes

Effects of the weld groove shape and geometry on residual stresses in dissimilar butt-welded pipes Original Article Effects of the weld groove shape and geometry on residual stresses in dissimilar butt-welded pipes J Strain Analysis 47(2) 73 82 Ó IMechE 2012 Reprints and permissions: sagepub.co.uk/journalspermissions.nav

More information

Nonlinear Finite Element Modeling & Simulation

Nonlinear Finite Element Modeling & Simulation Full-Scale Structural and Nonstructural Building System Performance during Earthquakes & Post-Earthquake Fire A Joint Venture between Academe, Industry and Government Nonlinear Finite Element Modeling

More information

CHAPTER 5 FINITE ELEMENT MODELING

CHAPTER 5 FINITE ELEMENT MODELING CHAPTER 5 FINITE ELEMENT MODELING 5.1 INTRODUCTION Masonry is a composite material with the building brick units and the mortar as the joining material, which are bonded together. Guinea [2000] 51 reported

More information

CHAPTER 6 FINITE ELEMENT ANALYSIS

CHAPTER 6 FINITE ELEMENT ANALYSIS 105 CHAPTER 6 FINITE ELEMENT ANALYSIS 6.1 INTRODUCTION Several theoretical approaches are considered to analyze the yielding and buckling failure modes of castellated beams. Elastic Finite Element Analysis

More information

CHAPTER 4 STRENGTH AND STIFFNESS PREDICTIONS OF COMPOSITE SLABS BY FINITE ELEMENT MODEL

CHAPTER 4 STRENGTH AND STIFFNESS PREDICTIONS OF COMPOSITE SLABS BY FINITE ELEMENT MODEL CHAPTER 4 STRENGTH AND STIFFNESS PREDICTIONS OF COMPOSITE SLABS BY FINITE ELEMENT MODEL 4.1. General Successful use of the finite element method in many studies involving complex structures or interactions

More information

INTERNATIONAL JOURNAL OF CIVIL AND STRUCTURAL ENGINEERING Volume 2, No 2, 2011

INTERNATIONAL JOURNAL OF CIVIL AND STRUCTURAL ENGINEERING Volume 2, No 2, 2011 INTERNATIONAL JOURNAL OF CIVIL AND STRUCTURAL ENGINEERING Volume 2, No 2, 2011 Copyright 2010 All rights reserved Integrated Publishing services Research article ISSN 0976 4399 Nonlinear Seismic Behavior

More information

Bearing and Delamination Failure Analysis of Pin Loaded Composite Laminates

Bearing and Delamination Failure Analysis of Pin Loaded Composite Laminates Volume 6, No. 2, February 217 1 Bearing and Delamination Failure Analysis of Pin Loaded Composite Laminates V. Dinesh Babu, Professor, Nehru Institute of Engineering and Technology, Coimbatore T. Sivagangai,

More information

LOAD RESPONSE AND FAILURE OF THICK RTM COMPOSITE LUGS

LOAD RESPONSE AND FAILURE OF THICK RTM COMPOSITE LUGS ICAS2 CONGRESS LOAD RESPONSE AND FAILURE OF THICK RTM COMPOSITE LUGS Markus Wallin 1, Olli Saarela 1 and Francesco Pento 2 1 Helsinki University of Technology and 2 Patria Finavicomp Keywords: composite

More information

3-D FINITE ELEMENT ANALYSIS OF PILE-TO-PILE CAP CONNECTIONS SUBJECTED TO SEISMIC ACTION

3-D FINITE ELEMENT ANALYSIS OF PILE-TO-PILE CAP CONNECTIONS SUBJECTED TO SEISMIC ACTION 3-D FINITE ELEMENT ANALYSIS OF PILE-TO-PILE CAP CONNECTIONS SUBJECTED TO SEISMIC ACTION M. Teguh 1,2), C.F. Duffield 1), P. A. Mendis 1), G.L. Hutchinson 1) 1) University of Melbourne, Melbourne, Victoria

More information

A Critical Comparative Study of Welding Simulations Using FEA

A Critical Comparative Study of Welding Simulations Using FEA A Critical Comparative Study of Welding Simulations Using FEA Narayanamoorthy Kathari 1, K. Ramesh Reddy 2, J. Bharat Kalyan 3 PG Student, Annamacharya Institute of Technology and Sciences (AITS), Tirupati,

More information

THE STUDY OF THE OVER STRENGTH FACTOR OF STEEL PLATE SHEAR WALLS BY FINITE ELEMENT METHOD

THE STUDY OF THE OVER STRENGTH FACTOR OF STEEL PLATE SHEAR WALLS BY FINITE ELEMENT METHOD THE STUDY OF THE OVER STRENGTH FACTOR OF STEEL PLATE SHEAR WALLS BY FINITE ELEMENT METHOD Mahin Abdollahzadeh 1, *Arman Kabiri 1 and Ramin Amjadi 2 1 Department of Civil Engineering, Islamic Azad University,

More information

SYSWELD Complete Finite Element Solution for Simulation of Welding Processes. Josef Tejc MECAS ESI s.r.o., CZ

SYSWELD Complete Finite Element Solution for Simulation of Welding Processes. Josef Tejc MECAS ESI s.r.o., CZ SYSWELD Complete Finite Element Solution for Simulation of Welding Processes Josef Tejc MECAS ESI s.r.o., CZ Company introduction Uslavska 10, Pilsen Czech Republic e-mail: info@mecasesi.cz web-page: http://www.mecasesi.cz

More information

ELASTIC AND ELASTO-PLASTIC BUCKLING ANALYSIS OF PERFORATED STEEL PLATES

ELASTIC AND ELASTO-PLASTIC BUCKLING ANALYSIS OF PERFORATED STEEL PLATES ELASTIC AND ELASTO-PLASTIC BUCKLING ANALYSIS OF PERFORATED STEEL PLATES MAURO DE VASCONCELLOS REAL 1, LIÉRCIO ANDRÉ ISOLDI 2, ALEXANDRA PINTO DAMAS 3, DANIEL HELBIG 4 ABSTRACT Many steel structures such

More information

APPLICATION OF MSC.Marc TO THE PREDICTION OF WELDED RESIDUAL STRESSES

APPLICATION OF MSC.Marc TO THE PREDICTION OF WELDED RESIDUAL STRESSES APPLICATION OF MSC.Marc TO THE PREDICTION OF WELDED RESIDUAL STRESSES Reference: 2001-60 Crown Copyright 2001/DERA QinetiQ + Farnborough, Hampshire, GU14 6TD, UK 1 G.P. Campsie, 2 A.C. Ramsay and 1 J.D.

More information

Numerical Studies on Residual Stress and Strain Distribution in Thick-welded Plate

Numerical Studies on Residual Stress and Strain Distribution in Thick-welded Plate AIJSTPME (2012) 5(4): 65-71 Numerical Studies on Residual Stress and Strain Distribution in Thick-welded Plate Chand R. R., Kim I. S., Lee J. H., Jung S. M. and Lee J. P. Department of Mechanical Engineering,

More information

Plastic deformation regularity of tailor-welded tube hydroforming

Plastic deformation regularity of tailor-welded tube hydroforming Indian Journal of Engineering & Materials Sciences Vol. 17, February 2010, pp. 13-19 Plastic deformation regularity of tailor-welded tube hydroforming Guannan Chu a * & Feng Li b a School of Naval Architecture,

More information

Thermo-Mechanical Modeling of Single High Power Diode Laser Welds

Thermo-Mechanical Modeling of Single High Power Diode Laser Welds Third LACCEI International Latin American and Caribbean Conference for Engineering and Technology (LACCET 2005) Advances in Engineering and Technology: A Global Perspective, 8-10 June 2005, Cartagena de

More information

Deformation and Energy Absorption of Aluminum Square Tubes with Dynamic Axial Compressive Load* 1

Deformation and Energy Absorption of Aluminum Square Tubes with Dynamic Axial Compressive Load* 1 Materials Transactions, Vol. 44, No. 8 (23) pp. 1566 to 157 #23 The Japan Institute of Light Metals Deformation and Energy Absorption of Aluminum Square Tubes with Dynamic Axial Compressive Load* 1 Makoto

More information

Three Dimensional Analysis Of Fits And Effect Of Layer Orientation In Laminated Composites Under Press Fits For Static And Dynamic Stability

Three Dimensional Analysis Of Fits And Effect Of Layer Orientation In Laminated Composites Under Press Fits For Static And Dynamic Stability ǁ Volume 1 Issue 3ǁAugust 2015 ǁ PP 37-42 Three Dimensional Analysis Of Fits And Effect Of Layer Orientation In Laminated Composites Under Press Fits For Static And Dynamic Stability Prapul Chandra AC

More information

Chapter 7. Finite Elements Model and Results

Chapter 7. Finite Elements Model and Results Chapter 7 Finite Elements Model and Results 7.1 Introduction In this chapter, a three dimensional model was presented. The analytical model was developed by using the finite elements method to simulate

More information

ON THE ANALYSIS OF A COLD FORMED STEEL PROFILE ARCH STRUCTURE

ON THE ANALYSIS OF A COLD FORMED STEEL PROFILE ARCH STRUCTURE Proceedings of the Annual Symposium of the Institute of Solid Mechanics and Session of the Commission of Acoustics, SISOM 2015 Bucharest 21-22 May ON THE ANALYSIS OF A COLD FORMED STEEL PROFILE ARCH STRUCTURE

More information

Advances in Engineering Research (AER), volume 102 Second International Conference on Mechanics, Materials and Structural Engineering (ICMMSE 2017)

Advances in Engineering Research (AER), volume 102 Second International Conference on Mechanics, Materials and Structural Engineering (ICMMSE 2017) Second International Conference on Mechanics, Materials and Structural Engineering (ICMMSE 2017) Modelling the influence of friction coefficient on materials process by Equal Channel Angular Press technique

More information

Three Dimensional Modeling of Masonry Structures and Interaction of In- Plane and Out-of-Plane Deformation of Masonry Walls

Three Dimensional Modeling of Masonry Structures and Interaction of In- Plane and Out-of-Plane Deformation of Masonry Walls Three Dimensional Modeling of Masonry Structures and Interaction of In- Plane and Out-of-Plane Deformation of Masonry Walls Kiarash M. Dolatshahi a and Amjad J. Aref b a Ph.D Candidate, Department of Civil,

More information

A New Standard for Radiographic Acceptance Criteria for Steel Castings

A New Standard for Radiographic Acceptance Criteria for Steel Castings Paper 09-118.pdf, Page 1 of 11 A New Standard for Radiographic Acceptance Criteria for Steel Castings Copyright 2009 American Foundry Society M. Blair, R. Monroe Steel Founders Society of America, Crystal

More information

Study on ultimate strength of ship plates with calculated weld-induced residual stress

Study on ultimate strength of ship plates with calculated weld-induced residual stress Maritime Technology and Engineering Guedes Soares & Santos (Eds) 2015 Taylor & Francis Group, London, ISBN 978-1-138-02727-5 Study on ultimate strength of ship plates with calculated weld-induced residual

More information

Numerical Simulation of Arc Welding Investigation of various Process and Heat Source Parameters

Numerical Simulation of Arc Welding Investigation of various Process and Heat Source Parameters Failure of Engineering Materials & Structures Code 30 UET TAXILA MECHNICAL ENGINEERING DEPARTMENT Numerical Simulation of Arc Welding Investigation of various Process and Heat Source Parameters M. Afzaal

More information

ScienceDirect. Finite Element Simulation of a Mercantile Vessel Shipboard Under Working Conditions

ScienceDirect. Finite Element Simulation of a Mercantile Vessel Shipboard Under Working Conditions Available online at www.sciencedirect.com ScienceDirect Procedia Engineering 69 ( 2014 ) 1001 1007 24th DAAAM International Symposium on Intelligent Manufacturing and Automation, 2013 Finite Element Simulation

More information

Bolt Study Behaviour of Bolts in Drop Accident Scenarios of the Nirex 3m³ Box ILW Package

Bolt Study Behaviour of Bolts in Drop Accident Scenarios of the Nirex 3m³ Box ILW Package 14th International Symposium on the Packaging and Paper # 109 Transportation of Radioactive Materials (PATRAM 2004), Berlin, Germany, September 20-24, 2004 Bolt Study Behaviour of Bolts in Drop Accident

More information

ELASTO-PLASTIC BEHAVIOR OF HORIZONTAL HAUNCHED BEAM-TO- COLUMN CONNECTION

ELASTO-PLASTIC BEHAVIOR OF HORIZONTAL HAUNCHED BEAM-TO- COLUMN CONNECTION ELASTO-PLASTIC BEHAVIOR OF HORIZONTAL HAUNCHED BEAM-TO- COLUMN CONNECTION Naoki TANAKA 1, Yoshikazu SAWAMOTO 2 And Toshio SAEKI 3 SUMMARY In response to the 1995 Hyogoken-Nanbu earthquake, horizontal haunched

More information

Thermal analysis of Laser Transmission Welding of thermoplastics: indicators of weld seam quality

Thermal analysis of Laser Transmission Welding of thermoplastics: indicators of weld seam quality Lasers in Manufacturing Conference 015 Thermal analysis of Laser Transmission Welding of thermoplastics: indicators of weld seam quality Adhish Majumdar* a, Benjamin Lecroc a, Laurent D Alvise a a Geonx

More information

BUCKLING ANALYSIS OF PULTRUDED GFRP HOLLOW BOX BEAM

BUCKLING ANALYSIS OF PULTRUDED GFRP HOLLOW BOX BEAM BUCKLING ANALYSIS OF PULTRUDED GFRP HOLLOW BOX BEAM Donna CHEN Ph.D. Candidate University of Calgary, Department of Civil Engineering 2500 University Drive NW, Calgary, Alberta, T2N 1N4, Canada dsmchen@ucalgary.ca

More information

The Effect of Axial Force on the Behavior of Flush End-Plate Moment Connections

The Effect of Axial Force on the Behavior of Flush End-Plate Moment Connections The Effect of Axial Force on the Behavior of Flush End-Plate Moment Connections A. Goudarzi, M. Ghassemieh & M. Baei School of Civil Engineering, University of Tehran, Tehran, Iran SUMMARY: An approach,

More information

FINITE ELEMENT MODELING OF CONCENTRICALLY BRACED FRAMES FOR EARTHQUAKES

FINITE ELEMENT MODELING OF CONCENTRICALLY BRACED FRAMES FOR EARTHQUAKES 13 th World Conference on Earthquake Engineering Vancouver, B.C., Canada August 1-6, 24 Paper No. 2816 FINITE ELEMENT MODELING OF CONCENTRICALLY BRACED FRAMES FOR EARTHQUAKES Madhar Haddad 1, Tom Brown

More information

THERMAL FATIGUE PROBLEMS OF TURBINE CASING

THERMAL FATIGUE PROBLEMS OF TURBINE CASING Fatigue of Aircraft Structures Vol. 1 (2009) 205-211 10.2478/v10164-010-0018-6 THERMAL FATIGUE PROBLEMS OF TURBINE CASING Lucjan Witek Daniel Musili Ngii Tadeusz Kowalski Rzeszów University of Technology,

More information

An example of finite element modelling of progressive collapse

An example of finite element modelling of progressive collapse COST Action TU0601 Robustness of Structures 2nd and 3rd of March 2009 Coimbra, Portugal An example of finite element modelling of progressive collapse Leslaw KWASNIEWSKI Marian A. GIZEJOWSKI Faculty of

More information

Investigation of factors influencing welding deformation of ship block by inherent strain analysis using idealized explicit FEM

Investigation of factors influencing welding deformation of ship block by inherent strain analysis using idealized explicit FEM Journal of Physics: Conference Series Investigation of factors influencing welding deformation of ship block by inherent strain analysis using idealized explicit FEM To cite this article: Masashi Hata

More information

Increased plastic strains in containment steel liners due to concrete cracking and discontinuities in the containment structure

Increased plastic strains in containment steel liners due to concrete cracking and discontinuities in the containment structure Increased plastic strains in containment steel liners due to concrete cracking and discontinuities in the containment structure Patrick Anderson 1) and Ola Jovall 2) 1) Division of Structural Engineering,

More information

Burst Pressure Prediction of Cylindrical Shell Intersection

Burst Pressure Prediction of Cylindrical Shell Intersection Burst Pressure Prediction of Cylindrical Shell Intersection Liping Xue, G. E. O. Widera Marquette University Center for Joining and Manufacturing Assembly Milwaukee, Wisconsin 53201 Zhifu Sang Nanjing

More information

STRENGTH OF PLATES OF RECTANGULAR INDUSTRIAL DUCTS

STRENGTH OF PLATES OF RECTANGULAR INDUSTRIAL DUCTS Available online at www.sciencedirect.com Procedia Engineering 14 (2011) 622 629 The Twelfth East Asia-Pacific Conference on Structural Engineering and Construction STRENGTH OF PLATES OF RECTANGULAR INDUSTRIAL

More information

SIMULATION AND VALIDATION OF WELDED JOINTS OF HIGH STRENGTH STEEL SHEETS

SIMULATION AND VALIDATION OF WELDED JOINTS OF HIGH STRENGTH STEEL SHEETS 6 th International Conference from Scientific Computing to Computational Engineering 6 th IC-SCCE Athens, 9-12 July, 2014 IC-SCCE SIMULATION AND VALIDATION OF WELDED JOINTS OF HIGH STRENGTH STEEL SHEETS

More information

NUMERICAL SIMULATION OF CIRCULAR HOLLOW STEEL COLUMNS CONFINED WITH FIBER REINFORCED POLYMER UNDER AXIAL COMPRESSION

NUMERICAL SIMULATION OF CIRCULAR HOLLOW STEEL COLUMNS CONFINED WITH FIBER REINFORCED POLYMER UNDER AXIAL COMPRESSION Proceedings of the 3 rd International Conference on Civil Engineering for Sustainable Development (ICCESD 2016), 12~14 February 2016, KUET, Khulna, Bangladesh (ISBN: 978-984-34-0265-3) NUMERICAL SIMULATION

More information

Nonlinear Models of Reinforced and Post-tensioned Concrete Beams

Nonlinear Models of Reinforced and Post-tensioned Concrete Beams 111 Nonlinear Models of Reinforced and Post-tensioned Concrete Beams ABSTRACT P. Fanning Lecturer, Department of Civil Engineering, University College Dublin Earlsfort Terrace, Dublin 2, Ireland. Email:

More information

GLOBAL RATCHETING BY ELASTIC-PLASTIC FEA ACCORDING TO ASME SECTION VIII RULES

GLOBAL RATCHETING BY ELASTIC-PLASTIC FEA ACCORDING TO ASME SECTION VIII RULES Proceedings of the ASME 2011 Pressure Vessels & Piping Division Conference Proceedings of PVP2011 2011 ASME Pressure July Vessels 17-21, and 2011, Piping Baltimore, Division Maryland, Conference USA July

More information

Welding Simulation and calculation of residual stresses. Dr.-Ing. Tobias Loose

Welding Simulation and calculation of residual stresses. Dr.-Ing. Tobias Loose Welding Simulation and calculation of residual stresses Dr.-Ing. Tobias Loose 17.11.2010 1 Causality 1. Welding torch 2. Temperature field 3. Elongation - shrinking Mechanical response of component Residual

More information

Critical J-Integral of Thin Aluminium Sheets Employing a Modified Single Edge Plate Specimen

Critical J-Integral of Thin Aluminium Sheets Employing a Modified Single Edge Plate Specimen Vol.2, Issue.3, May-June 2012 pp-1360-1365 ISSN: 2249-6645 Critical J-Integral of Thin Aluminium Sheets Employing a Modified Single Edge Plate Specimen P. S. Shinde 1, K. K. Singh 2, V. K. Tripathi 1,

More information

FEM model of induction hardening of gear of mixture material

FEM model of induction hardening of gear of mixture material Volume 71 Issue 2 August 2015 of Achievements in Materials and Manufacturing Engineering International Scientific Journal published monthly by the World Academy of Materials and Manufacturing Engineering

More information

BEHAVIOUR OF COLD-FORMED Z-SHAPED STEEL PURLIN IN FIRE

BEHAVIOUR OF COLD-FORMED Z-SHAPED STEEL PURLIN IN FIRE BEHAVIOUR OF COLD-FORMED Z-SHAPED STEEL PURLIN IN FIRE ABSTRACT Wei Lu *, Pentti Mäkeläinen *, Jyri Outinen ** * Department of Civil and Structural Engineering Aalto University, Espoo, Finland Wei.Lu@tkk.fi,

More information

Fatigue Strength Analysis on the Automobile Stabilizer Bar Based on ANSYS

Fatigue Strength Analysis on the Automobile Stabilizer Bar Based on ANSYS Send Orders for Reprints to reprints@benthamscience.ae The Open Mechanical Engineering Journal, 2014, 8, 619-623 619 Open Access Fatigue Strength Analysis on the Automobile Stabilizer Bar Based on ANSYS

More information

Compressive strength of double-bottom under alternate hold loading condition

Compressive strength of double-bottom under alternate hold loading condition Progress in the Analysis and Design of Marine Structures Guedes Soares & Garbatov (Eds) 017 Taylor & Francis Group, London, ISBN 978-1-138-06907-7 Compressive strength of double-bottom under alternate

More information